Skeinforge Dimension

From DEMOZENDIUM

Jump to: navigation, search

Skeinforge Contents

Dimension adds Adrian's extruder distance E value so firmware does not have to calculate it on it's own and can set the extruder speed in relation to the distance that needs to be extruded. Some printers don't support this. Extruder distance is described at:

http://blog.reprap.org/2009/05/4d-printing.html

and in Erik de Bruijn's conversion script page at:

http://objects.reprap.org/wiki/3D-to-5D-Gcode.php

Nophead wrote an excellent article on how to set the filament parameters:

http://hydraraptor.blogspot.com/2011/03/spot-on-flow-rate.html

Contents

Operation

The default 'Activate Dimension' checkbox is off. When it is on, the functions described below will work, when it is off, the functions will not be called.

Settings

Extrusion Distance Format Choice

Default is Absolute Extrusion Distance because in Adrian's description the distance is absolute. In future, because the relative distances are smaller than the cumulative absolute distances, hopefully the firmware will be able to use relative distance.

Absolute Extrusion Distance

When selected, the extrusion distance output will be the total extrusion distance to that gcode line.

Relative Extrusion Distance

When selected, the extrusion distance output will be the extrusion distance from the last gcode line.

Extruder Retraction Speed

Default: 13.3 mm/s.

Defines the extruder retraction feed rate. A high value will allow the retraction operation to complete before much material oozes out. If your extruder can handle it, this value should be much larger than your feed rate.

As an example, I have a Feed Rate of 48 mm/s and a Extruder Retraction Speed of 150 mm/s.

If you are having issues with over-extrusion wherever retracts occurs, you may have your retract speed set too high. Too high a speed can cause the extrusion stepper motor to skip steps when reversing, then when it re-extrudes the retraction distance, the net amount of plastic extruded is > 0 instead of 0.

Filament

Filament Diameter

Default: 2.8 mm

Defines the filament diameter.

This should be an accurate measurement of the actual filament dimension using calipers (not simply what the manufacturer says it is). The filament should be measured in several places and the results averaged.

Filament Packing Density

Default: 0.85 This is for ABS.

Defines the effective filament packing density. If you previously used Slic3r, it's the same as Extrusion Multiplier. It's a setting that lets you tweak your e-steps (without having the re-flash the firmware) to compensate for different filament hardnesses.

The default value assumes you calibrated your e-steps using PLA, but are printing with ABS. If you are printing with the material you calibrated your e-steps with, you should set this value to 1. If you later want to print with different materials, you'll need to tweak this value or recalibrate your e-steps and update that value in the firmware.

The default value is so low for ABS because ABS is relatively soft and with a pinch wheel extruder the teeth of the pinch dig in farther, so it sees a smaller effective diameter. With a hard plastic like PLA the teeth of the pinch wheel don't dig in as far, so it sees a larger effective diameter, so feeds faster, so for PLA the value should be around 0.97. This is with Wade's hobbed bolt. The effect is less significant with larger pinch wheels.

Overall, you'll have to find the optimal filament packing density by experiment.

Maximum E Value before Reset

Default: 91234.0

Defines the maximum E value before it is reset with the 'G92 E0' command line. The reason it is reset only after the maximum E value is reached is because at least one firmware takes time to reset. The problem with waiting until the E value is high before resetting is that more characters are sent. So if your firmware takes a lot of time to reset, set this parameter to a high value, if it doesn't set this parameter to a low value or even zero.

Minimum Travel for Retraction

Default: 1.0 mm

Defines the minimum distance that the extruder head has to travel from the end of one thread to the beginning of another, in order to trigger the extruder retraction. Setting this to a high value means the extruder will retract only occasionally, setting it to a low value means the extruder will retract most of the time.

Retract Within Island

Default: off

When selected, retraction will work even when the next thread is within the same island. If it is not selected, retraction will only work when crossing a boundary.

Retraction Distance

Default: 0 mm

Defines the amount the extruder retracts (sucks back) the extruded filament whenever an extruder stop is commanded. Using this seems to help prevent stringing. e.g. If set to 10 the extruder reverses the distance required to pull back 10mm of filament. In fact this does not actually happen but if you set this distance by trial and error you can get to a point where there is very little ooze from the extruder when it stops which is not normally the case.

Restart Extra Distance

Default: 0 mm

Defines the restart extra distance when the thread restarts. The restart distance will be the retraction distance plus the restart extra distance.

If this is greater than zero when the extruder starts this distance is added to the retract value giving extra filament. It can be a negative value in which case it is subtracted from the retraction distance. On some Repstrap machines a negative value can stop the build up of plastic that can occur at the start of perimeters.

Personal tools